Create a multi-axis setup in Fusion

00:03

While most parts can be manufactured using standard two D and 3D tool parts,

00:07

there is significant value and efficiency in

00:10

using three plus two or positional multi

00:13

axis strategies to make parts that would otherwise

00:16

require several setups like the scanty upright.

00:21

I'll be programming this upright in the context of an assembly.

00:24

So first,

00:26

I'll need to locate the component by double clicking on it in the workspace.

00:29

And following the hash marks under the components in my browser,

00:34

I'll activate the upright and then use the derive function to separate

00:38

the part into a separate document whilst maintaining all of its associative

00:43

derive ensures that any design changes made to the model

00:46

in the assembly are propagated forward throughout the document.

00:52

Doing this has several advantages over

00:54

isolating components and is particularly important in

00:57

making sure most recent versions of the design are used when programming the part

01:03

while it was optional to model in fixtures,

01:06

while programming two D and 3D tool paths,

01:08

it's much more important in multi

01:10

axis because collisions are much more likely when

01:12

the part is consistently reorientating in the machine.

01:16

So I'm going to choose a fixture to use

01:18

model my stock and then insert that fixture into the design.

01:25

It's important to note that the derive option we used

01:28

is only associative from when the derive operation was performed.

01:32

Bringing in the dovetail fixture will have no impact

01:35

on the assembly in which the upright is based.

01:39

I have the dovetail design specs from the manufacturer to

01:42

use whilst designing the stock body around the upright.

01:46

First,

01:47

I'll create a new sketch using the face of the upright as a sketch plane.

01:51

The first step is sketching a 10 inch by

01:58

Then

01:59

I'll use a bore hole on the upright to position

02:02

the upright within the outer contour of the stock.

02:06

Now I'm ready to start sketching the

02:08

dovetails based on the manufacturer's specifications.

02:12

Starting with the general shape of the dovetails

02:15

to learn the basics of sketching.

02:17

Refer to the create component video in the mechanical assemblies path.

02:21

Those basic sketch principles are what I'm applying here to

02:24

create the dovetails as defined in the manufacturing specs.

02:29

All the sketch edges are black

02:31

indicating that the sketch is fully constrained.

02:34

I can hit stop sketch to exit the sketch environment.

02:38

I'll select the extrude command to start making some solid geometry.

02:43

I'll select the closed sketch profile and rather

02:46

than starting right from the sketch plane,

02:48

I'll add an offset of 50 thousands.

02:51

Then I'll extrude to the opposite face of the upright,

02:55

adding another offset of 50/1000.

02:57

Finally

02:59

I want to change the operation to new body to make sure I'm creating a stock body,

03:05

I'll hit OK.

03:06

And the stock body with dovetails is generated.

03:10

Next,

03:11

I need to add a locating slot to the bottom of the

03:14

dovetails to line up with the locating pin on the dovetail vice.

03:19

I'll refer to the manufacturer specs again to define the size of the slot

03:23

and then I'll create an extruded cut

03:25

to the flat face of the stock.

03:40

I have a Raptor dovetail V

03:42

which has solid models available in the samples. Projects in fusion 360.

03:47

I'll navigate to the cam samples project

03:50

into the work holding folder

03:52

and then to Raptor work holding.

03:54

I have an RWP 401 11.

03:58

So I'll open the design and save it to

03:60

the same project and folder as the upright assembly

04:04

to insert it into the upright assembly.

04:06

I'll navigate back to the folder in my data panel. Right? Click on the Raptor device

04:11

and select insert into current design.

04:15

Now I'm ready to put the stock and the vice together.

04:18

I'll use a joint based on the center point of the locating pin

04:22

and the center point of the radius of the locating slot in the stock

04:26

to learn more about what a joint is

04:28

and how I'm selecting these joint origin locations

04:31

and why I need to add 100 and 80 degree offset.

04:34

Refer to the assembly's and joint video in the mechanical assembly's path.

04:40

Now I have my stock and fixture modeled in relative to the upright.

04:44

So I'm ready to move into the manufacturing workspace and create a setup

04:48

to create a setup for positional multi

04:50

access

04:51

machining.

04:52

I want to keep milling as the operation type.

04:55

While defining the work coordinate system, I want to align it to how I will be probing

05:00

or locating the part in my machine.

05:03

So in this case,

05:04

I would likely locate the midpoint of the fixture for X and Y

05:08

and then use the bottom face of the fixture to define Z

05:12

to more easily, select off the vice.

05:15

I'll use the browser to toggle the visibility of the upright and the stock body.

05:20

I'll define X and Z using the face and the edge of the dovetail portion of the fixture

05:26

and use selected point to define the origin as the

05:28

top edge of the center hole of the vice.

05:32

I'll also use the browser tree to select the upright body as the model

05:36

and select the RWP 401 11 body as the fixture

05:42

in the stock tab. I'll define my stock from solid

05:45

and choose the stock body from the workspace or from the browser tree.

05:51

Finally, in the post process tab,

05:54

I'll set the work coordinate system offset value to one.

05:57

Now, my setup is done and I'm ready to start creating operations.